RE: [mfg-smartcam] M29

[John Coulston]

My control Fanuc OM needs the S with the M29 not the first positioning move like a normal tool.  Add the following at the beginning of the file and were ever you have a tool change event.     Checks to see if it is a tap and that the tapping cycle is set to 2 in the process operation.   #EVAL(#cyc=jos(cycle)) #EVAL(#type=jos(op_type)) #IF(#cyc=1,#AND#type=206)<  G90 G54< #MOV>< #DCOMP#EXC D#DOFF> X#XPOS Y#YPOS T#NTOOL >#ELSE<  G90 G54< #MOV>< #DCOMP#EXC D#DOFF> X#XPOS Y#YPOS #SPNDL S#SPEED T#NTOOL >           // tap @OP_TAP // Use G74 (M04=left hand tapping) or G84 (M03=tapping cycle) #IF(#U1)<#RESET(#CYCLE,#XPOS,#YPOS,#ZDPTH,#CLEAR,#FEED,#top)#EVAL(#U1=0)#EVAL(#U2=1)#EVAL(#U3=0)#EVAL(#U4=0)#EVAL(#count=0)> #IFCHG(#CYCLE)<#RESET(#XPOS,#YPOS,#FEED,#CYCLE)> #IFCHG(#ZDPTH)<#RESET(#CYCLE,#ZDPTH,#CLEAR,#FEED)>/// recodes cycle feed and R if depth of hole changes #IF(#CYCLE=1,AND #U4=0)<#CALL(RIDGED)> // <#ABSI>< #CYCLE>< X#XPOS>< Y#YPOS>< Z#ZDPTH R#top>< F#FEED>//<a#RTNLVL> probably wont need #rtnvvl G98 set by SMF q173-175 #ONBLK // // @@CYCLE 0,G85 1,G84 2, @   @RIDGED  M29 S#SPEED #EVAL(#U4=1) @       HTH John Coulston   CBR Industries, Inc. CNC Milling & Turning www.cbrcnc.com   -----Original Message----- From: [EMAIL PROTECTED] [mailto:[EMAIL PROTECTED]]On Behalf Of Michael Mamontov Sent: Friday, August 10, 2001 1:33 PM To: [EMAIL PROTECTED] Subject: [mfg-smartcam] M29   Need insert M29( rig. tapping) before G84 CODE MUST LOOKS LIKE M29 G84 X0. Y0.Z-.25 R.1 F4.0 X1. Y1.0 ETC.   ANY HELP ?