Kevin,
Here is my section at 100% feed.
@FXD4
G32 Z#ZPASS F#FMT(#FTHRD,D1.6) #SPNDL
M5
#IF(#SPNDL=1)<#EVAL(#SPNDL=2)>#ELSE<#EVAL(#SPNDL=1)>
G32 Z#ZPOS F#FMT(#FTHRD,D1.6) #SPNDL
change F#FMT TO E#FMT
Dave Wolfgang
CNC Programmer/Supervisor
www.hrindustries.net
----- Original Message -----
From: "Kevin Brown" <[EMAIL PROTECTED]>
To: "Dave Wolfgang" <[EMAIL PROTECTED]>;
<[EMAIL PROTECTED]>; <[EMAIL PROTECTED]>
Sent: Tuesday, October 16, 2001 2:41 PM
Subject: Re:
> Dave,
>
> Thanks for your help, here's whats going on, this is what is was like,
>
>
>
> @FXD4
> G1 Z#ZPASS F#FEED M05
> #EVAL(#FEED=#FEED*1.1)
> G1 Z#ZPOS F#FEED M04
> M05
> M03
>
> The code is processed as such...
>
> N790 M1 ;
> N795 M98 P1;
> N800 G0 X5.0 Z3.0 T0500 M9 ;
> N805 T0600 ( L 0.250 DIA. FIXED TAP MIKE MADE THIS TAP, );
> N810 G97 S800 F0.0417 M3;
> N815 G0 X0.0 Z0.1 T0606 M8;
> N820 G1 Z-0.748 F0.0417 M05;
> N825 ;
> N830 G1 Z0.1 F0.0458 M04;
> N835 M05;
> N840 M03;
> N845 G0 X5.0 Z3.0 T0600 M9;
> N850 M98 P2;
> N855 M30;
>
>
> This is what I did to it as per your instructions, I also changed the smf
to
> D2.6,
>
> @FXD4
> G1 Z#ZPASS F#FEED M05
> F#FMT(#FTHRD,D1.6)
> G1 Z#ZPOS F#FEED M04
> M05
> M03
>
> The code is processed as such...
>
> N790 M1 ;
> N795 M98 P1;
> N800 G0 X5.0 Z3.0 T0500 M9 ;
> N805 T0600 ( L 0.250 DIA. FIXED TAP MIKE MADE THIS TAP, );
> N810 G97 S800 F0.0417 M3;
> N815 G0 X0.0 Z0.1 T0606 M8;
> N820 G1 Z-0.748 F0.0417 M05;
> N825 F0.041667 ;
> N830 G1 Z0.1 F0.0417 M04;
> N835 M05;
> N840 M03;
> N845 G0 X5.0 Z3.0 T0600 M9;
> N850 M98 P2;
> N855 M30;
>
>
> The programing manual calls for the format to be like this...
>
> G32 Z-.75 E.049
> G4 U.5
> G32 Z.25 E.050 M4
>
>
> Now if you don't mind I am anxiously seeking a solution to this problem so
> any help would be extreemly benificial, thank!
>
>
> Kevin Brown
> Technical Services
> Brock University
> St. Catharines, ONT
>
>
>
> On Mon, 15 Oct 2001 15:26:02 -0400, Dave Wolfgang wrote:
>
> > Kevin,
> > Edit your FXD4 section at the feed to look like this
> > F#FMT(#FTHRD,D1.6)
> >
> >
> > Dave Wolfgang
> > CNC Programmer/Supervisor
> > www.hrindustries.net
> >
> > ----- Original Message -----
> > From: "Kevin Brown" <[EMAIL PROTECTED]>
> > To: <[EMAIL PROTECTED]>
> > Sent: Monday, October 15, 2001 2:38 PM
> >
> >
> > > Hello,
> > >
> > >
> > > When I tap on the lathe smartcam rounds off to 3 dcimal places and
> that
> > > has caused me problems, how do I change that so it is good to say 6
> > > decimals? Thanks!
> > >
> > >
> > >
> > > Kevin Brown
> > > Technical Services
> > > Brock University
> > > St. Catharines, ONT
> > >
> > >
> > >
> > >
> > >
> > > _______________________________________________________
> > > Send a cool gift with your E-Card
> > > http://www.bluemountain.com/giftcenter/
> > >
> > >
> > >
======================================================================
> > > To find out more about this mailing list including how to
unsubscribe,
> > > send the message "info mfg-smartcam" to [EMAIL PROTECTED]
> > >
======================================================================
> > >
> >
>
>
> Kevin Brown
> Technical Services
> Brock University
> St. Catharines, ONT
>
>
>
>
>
> _______________________________________________________
> Send a cool gift with your E-Card
> http://www.bluemountain.com/giftcenter/
>
>
======================================================================
To find out more about this mailing list including how to unsubscribe,
send the message "info mfg-smartcam" to [EMAIL PROTECTED]
======================================================================
