Thanks!The "Compute Normals" is checked in the contour filter after the CleanToGrid filter, however the Gouraud shading does not work. But using an additional "Generate Surface Normals" then does the trick, at least partially. The contours look nicer than without Gouraud shading, obviously, but the best result (and also the cheapest one, I will use it on large data sets) would still be obtained when directly doing a contour on the original rectilinear data without transforming it to unstructured.
Thus, I was wondering whether I should submit the present case also as a bug report, as I guess also other people might need coloured isosurfaces when running MPI?
Best regards, PhilippOn Fri, 01 Jul 2011 15:53:18 +0200, pat marion <pat.mar...@kitware.com> wrote:
Hi Philipp,You need to check the "Compute Normals" box on the properties panel of the contour filter. Alternatively, you can apply the "Generate Surface Normals"to any polydata dataset to enable correct Gouraud shading. PatOn Wed, Jun 29, 2011 at 11:24 AM, Philipp Schlatter <pschl...@mech.kth.se>wrote:Thanks a lot for the help!Concerning the suggested workaround, I have a follow-up question: How would one get the Gouraud shading of the isocontours working? In my case I will get properly coloured isocontours, but they seem to have uniform shade foreach triangle as opposed to an interpolated shade. Thanks, philipp On Wed, 29 Jun 2011 14:34:34 +0200, Karl König <kkoeni...@web.de> wrote: Hi Philipp,It seems you have hit a bug in the Contour filter occurring with > 1 pvserver process and rectilinear grid input. I can reproduce the issue you reported as such: Load ParaView, connect to > 1 pvserver processes Open Data/RectGrid2.vtk (e.g. from git://vtk.org/VTKData.git) Calculator filter, operation: "coordsX", Result Array Name: "Result", Apply Contour filter, Contour by "scalars", Compute Normals, Isosurface Value 0.5, Apply Representation "Surface", Color by "Result" With 1 pvserver process the surface coloring is indeed a single smooth gradient while with more than 1 pvserver process the gradient startsanew at half the X range. If applying an additional "Process ID Scalars"filter, one can confirm that the "reset" happens at a process boundary. Converting the rectilinear grid to an unstructured grid prior to applying the contour filter may serve as as a workaround. The filters "Clean to Grid", "Tetrahedralize" and "Tesselate" all do that trick (they are listed with increasing memory footprint). So, I recommend using "Clean to Grid" somewhere before applying the contour filter in the parallel case. Karl Philipp Schlatter wrote, On 29.06.2011 11:50:Hi! Thanks for the answer. Let me give some comments to your questions:- I am using the distributed 3.10.1 binaries (32 bit), and I tried it ona Ubuntu 11.04 system (older dualcore T60p)- I used now the sample dataset Data/RectGrid2.vtk. Using the calculatoroperation "CoordsX", I can reproduce the behaviour I was originally describing. I simply use the Contour filter ("Compute Scalars" did not change the behaviour). I have uploaded 3 more screenshots: http://www.mech.kth.se/~**pschlatt/files/Screenshot3.png<http://www.mech.kth.se/%7Epschlatt/files/Screenshot3.png>is the intended result, obtained using a single core (no Auto-MPI etc.)http://www.mech.kth.se/~**pschlatt/files/Screenshot2.png<http://www.mech.kth.se/%7Epschlatt/files/Screenshot2.png> is the result obtained with Auto-MPI, running on my two cores. http://www.mech.kth.se/~**pschlatt/files/Screenshot1.png<http://www.mech.kth.se/%7Epschlatt/files/Screenshot1.png>is the result obtained with explicitly initiating paraview and pvserverusing a total of 16 MPI ranks.I tried all/most of the rendering options (LOD etc.), however it did nothelp. Also, I have run on 64 bit version at the computer centre (with older versions though), and the same problem appears there too. I am really puzzled by the fact that you could not reproduce theproblem. Could there be some setting that is for some reason wrong in mysetup? Best regards, PhilippOn Tue, 28 Jun 2011 18:36:25 +0200, Karl König <kkoeni...@web.de> wrote:Hi Philipp,A couple of questions: * Are you using the distributed 3.10.1 binaries or did you compile PV 3.10.1 from source yourself? * Can you reproduce the behavior with the sample dataset Data/RectGrid2.vtk (part of both git://vtk.org/VTKData.git and http://www.paraview.org/files/**v3.10/ParaViewData-3.10.1.zip<http://www.paraview.org/files/v3.10/ParaViewData-3.10.1.zip> )**? That's also a "Rectilinear Grid". Using the Calculator operation "1 + coordsX*coordsY" followed by a Contour filter with "Compute Scalars"checked and 10 auto-chosen values, I got identical results with 1 and 16cores (using PV 3.10.1 Linux 64-bit binaries and Windows 64-bitbinaries, relying on Auto-MPI ("Settings" - "Use Multi-Core") for the 16core case) Karl Philipp Schlatter wrote, On 28.06.2011 17:50:Dear all, Unfortunately, I am still struggling with running MPI and producing coloured isosurfaces. A screenshot exemplifying the problem can be found at http://www.mech.kth.se/~**pschlatt/files/Screenshot.png<http://www.mech.kth.se/%7Epschlatt/files/Screenshot.png>; note that the colour scheme based on the x-coordinate is just to show the problem, but in reality I am using some scalar data coming from file. Anyway, I wanted to ask you whether any of you has had similar problems, i.e. colouring isosurfaces when running MPI. It seems to me that the datafield used to colour the surfaces is only created on one MPI rank andthen used by all other ranks, instead of computed for each rank independently based on the local data. Can anyone confirm that behaviour? This problem makes it at the moment impossible for me to visualise a certainvery large data set as I need to use MPI to distribute the data due tomemory limitation. Thanks a lot for any help! Philipp -----Original Message----- From: Philipp Schlatter [mailto:pschl...@mech.kth.se] Sent: den 20 juni 2011 22:55 To: 'Utkarsh Ayachit' Cc: paraview@paraview.org Subject: RE: [Paraview] FW: Coloured isosurfaces when running MPI Dear Utkarsh,Thanks a lot for your answer. The type of my data is "Rectilinear Grid"(turbulence data on a regular grid). The test case that I use to reproduce the data leads to a size of the contours (from the statistics inspector)230316 cells, and a memory of 15 MB. I have turned off all the remoterender thresholds etc. and the problem persists. Thus it is likely that it is the contour filter that causes the miscolouring. I have just reroduced the problem using the latest version 3.10.1 (Linux 32-bit); and I generated a screenshot on http://www.mech.kth.se/~**pschlatt/files/Screenshot.png<http://www.mech.kth.se/%7Epschlatt/files/Screenshot.png> . The test is simple; I read in a rectilinear grid with a few velocity components. Then I compute a new scalar field, essentially being the x-corrdinate. Then I plot an isocontour, and colour it with the result ofthe calculator. I would expect a continuous colour going from blue tored spread over the whole x extent, however - according to the number of processors used (in that case 16) - I get a repetitive pattern. By some more experimenting it becomes clear that for some reason the colouring is done based on the scalar value on the first processor only. Running on 1 processor everything is fine. I am of course happy to provide the respective data files, if this could help. Thanks for any help! Best regards, Philipp -----Original Message-----From: Utkarsh Ayachit [mailto:utkarsh.ayachit@**kitware.com<utkarsh.ayac...@kitware.com>] Sent: den 20 juni 2011 16:59 To: Philipp Schlatter Cc: paraview@paraview.org Subject: Re: [Paraview] FW: Coloured isosurfaces when running MPI That's very peculiar. What datatype are you contouring? (With the reader selected in the pipeline browser, go to the information tab, what does the "Type" field say?) Also after generating the iso-surface, open the statistics inspector (View | Statistics Inspector). What is the size of thegeometry generated from the contour filter. If that's not too large,youtry doing local-rendering (go to Edit | Settings, on the Server page,uncheck Remote Render Threshold). Does that help? This will help diagnose ifthe issue is with rendering or with the data generated by the contourfilter itself. Utkarsh On Sun, Jun 19, 2011 at 11:25 AM, Philipp Schlatter <pschl...@mech.kth.se> wrote:Dear forum,I am using Paraview to visualise a large dataset coming from a directsimulation of turbulence (size of the original data of order 10-100GB). Naturally, I am running in parallel on a cluster (using the mesa), which also works very well. However, there is one issue: I want to visualise isosurfaces of aquantity, and colour them using another scalar quantity. When runningserial, everything is fine. When using multiple processors with MPI leading to the data being distributed, the rendering of the isosurfaces isstill ok.However, the colouring seems to be based on the scalar field of thefirst data segment (i.e. the first processor) only. This then leads tovery visible boundaries between the processors as the colours are clearly not correct (see example on http://www.mech.kth.se/~**pschlatt/files/resampled.jpg<http://www.mech.kth.se/%7Epschlatt/files/resampled.jpg>). Again, runningon a single processor everything is correct, and running on differentnumbers of processors will shift the edges. This issue could be confirmed in all version up to 3.10. Due to this, I am required to run in serial, which is very painfulboth due to memory requirements and very long rendering times (up to15 minutes for a single frame). Thus, if there would be a simple fix, I'dbe very interested.Thanks a lot in advance for any hint. Best regards, Philipp Schlatter KTH Mechanics, Stockholm, Sweden______________________________**_________________Powered by www.kitware.com Visit other Kitware open-source projects at http://www.kitware.com/** opensource/opensource.html<http://www.kitware.com/opensource/opensource.html> Please keep messages on-topic and check the ParaView Wiki at: http://paraview.org/Wiki/**ParaView <http://paraview.org/Wiki/ParaView> Follow this link to subscribe/unsubscribe: http://www.paraview.org/**mailman/listinfo/paraview<http://www.paraview.org/mailman/listinfo/paraview>
_______________________________________________ Powered by www.kitware.com Visit other Kitware open-source projects at http://www.kitware.com/opensource/opensource.html Please keep messages on-topic and check the ParaView Wiki at: http://paraview.org/Wiki/ParaView Follow this link to subscribe/unsubscribe: http://www.paraview.org/mailman/listinfo/paraview
