Michael,
Reading you most recent comments I now suspect that your relays are
being added to the PCB design. However they are being added outside of the
visible window, this is why when you tired to jump to them you ended up along
the edge of the window.
Check the relay footprint in the library, I am betting that it is not
located closely to the 0,0 reference point within the library. This is I would
suspect is shoving it outside of the screen region. They are probably there in
the design but just not in the visible screen region.
Next you will have to get rid of the components/relays ones that are out of the
positive quadrant. Usually it is best to Select All (keystrokes S, A), then use
Edit, Deselect Inside (keystrokes E,E,I) and draw a box around the main portion
of your board and components that you want to keep. Then delete the selected
components/items , using "SHIFT" & "Delete" keys. Read in your schematic
updates once again and if the relay footprints are correctly referenced to 0,0
they should come in in the viewable area this time.
Sincerely,
Brad Velander
Senior PCB Designer
Northern Airborne Technology
#14 - 1925 Kirschner Road,
Kelowna, BC, V1Y 4N7.
tel (250) 763-2329 ext. 225
fax (250) 762-3374
-----Original Message-----
From: Robison, Michael R NAVSEA [mailto:[EMAIL PROTECTED]
Sent: Tuesday, November 29, 2005 10:01 AM
To: Protel EDA Discussion List
Subject: RE: [PEDA] Components not transferring to PCB
Thank you, Peter and Brad, for your suggestions. I will attempt to
address both here.
First, I'm not getting any errors when doing the Update PCB, or at least
none that I see. When I was first attempting to get it to the PCB, it was
standard operating procedure to Preview Changes, click the "show errors
only" box, and then work through them. I also always make sure that I'm
not getting an extra tab for warnings. I do not execute the changes if
there are errors or warnings.
I do have a footprint assigned, and it shows in the same dropdown where I
see other PCB footprints that are apparently working successfully. I com-
pared the attributes to a diode on the same schematic page as the relays
and everything looked OK. Diodes and resistors on the same schematic page
as the relays are making their way to the PCB.
Let me note a couple of things I've looked at, prompted by your posts. I
do a jump to CR1 which is on the PCB and it takes the cursor right to it.
Just a reality check. THEN I jump to K1 and it rolls way off the board
and down to the border of the window. Nothing I can do seems to allow me
to go down lower, and I see nothing there. A quick look at the footprint
shows thru holes of normal size and a big yellow circle on the top overlay
with a notch in it indicating pin 1, so if it was in sight in the window,
it ought to show up. Same thing happens for K2. I do NOT see rat's nest
wires leading off the board anywhere. What do you make of all that? It
seems significant.
Let me mention the updates that it continually performs, even with no
addtional changes to the board. First it goes through several messages
like "Remove redundant net NetK3_2." Then a few messages like "Add new
net NetK3_2," and yes, it is removing and adding the exact same nets in
at least some cases.
I have mentioned that I was never extremely proficient in Protel. There
is a chance that I'm doing something incredibly dumb that would sail right
by you. With this in mind, I want to note the options I'm selecting in
the Design/Update PCB/Synchronizer. I have the Net labels and nets set
Global, and the ONLY other options I have selected are the "update com-
ponent footprints" and "delete components." Does that sound OK?
Again, I appreciate your help.
Thanks, Michael
____________________________________________________________
You are subscribed to the PEDA discussion forum
To Post messages:
mailto:[email protected]
Unsubscribe and Other Options:
http://techservinc.com/mailman/listinfo/peda_techservinc.com
Browse or Search Old Archives (2001-2004):
http://www.mail-archive.com/[email protected]
Browse or Search Current Archives (2004-Current):
http://www.mail-archive.com/[email protected]
