[Emc-users] Question for larger machine users of LCNC
This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. My question is how are others working around this? For instance I am working on a job machining gears with hardened teeth and we have to remove .250 form one face, roughing insert lasts about 2/3 of the way through the roughing program and we have to rotate the insert. Feed hold leaves us in a position too close to the part to change the insert. Our only solution is to exit program and move tool away to rotate insert and restart program from the beginning and cut air until we get back into the cut. We try to run from line but even if we call constant surface feed in our MDI spindle start the spindle runs at the cap RPM. Jeff Johnson john...@superiorroll.com Superior Roll Turning 734-279-1831 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
Perhaps you could tweak the program with a clearance move and optional stop at the expected insert change points? --Original Mail-- From: Jeff Johnson john...@superiorroll.com To: emc-users@lists.sourceforge.net Sent: Fri, 21 Nov 2014 09:40:04 -0500 Subject: [Emc-users] Question for larger machine users of LCNC This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. My question is how are others working around this? For instance I am working on a job machining gears with hardened teeth and we have to remove .250 form one face, roughing insert lasts about 2/3 of the way through the roughing program and we have to rotate the insert. Feed hold leaves us in a position too close to the part to change the insert. Our only solution is to exit program and move tool away to rotate insert and restart program from the beginning and cut air until we get back into the cut. We try to run from line but even if we call constant surface feed in our MDI spindle start the spindle runs at the cap RPM. Jeff Johnson john...@superiorroll.com Superior Roll Turning 734-279-1831 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
This doesn't directly answer your question about jog-while-paused, but I'm curious about the specific use case you describe. How do you decide when to change the insert? Do you wait until it chips or starts cutting poorly? Or do you always change it at the same point because you know it won't last all the way through? If you wait for it to chip or stop cutting properly, it seems to me that it isn't good enough to simply pause, jog away, change the insert, jog back, and resume. Don't you have to actually back up in the program a bit and re-machine the area that was improperly cut? On the other hand, if you have decided to always change the insert at the 2/3 mark just to be safe, then can't you simply program the change in the g-code? At the end of a pass, rapid over to a safe spot, stop the spindle, and do the change. Then start the next pass. On Fri, Nov 21, 2014, at 09:40 AM, Jeff Johnson wrote: This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. My question is how are others working around this? For instance I am working on a job machining gears with hardened teeth and we have to remove .250 form one face, roughing insert lasts about 2/3 of the way through the roughing program and we have to rotate the insert. Feed hold leaves us in a position too close to the part to change the insert. Our only solution is to exit program and move tool away to rotate insert and restart program from the beginning and cut air until we get back into the cut. We try to run from line but even if we call constant surface feed in our MDI spindle start the spindle runs at the cap RPM. Jeff Johnson john...@superiorroll.com Superior Roll Turning 734-279-1831 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- John Kasunich jmkasun...@fastmail.fm -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
On 11/21/2014 08:40 AM, Jeff Johnson wrote: This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. My question is how are others working around this? For instance I am working on a job machining gears with hardened teeth and we have to remove .250 form one face, roughing insert lasts about 2/3 of the way through the roughing program and we have to rotate the insert. Feed hold leaves us in a position too close to the part to change the insert. Our only solution is to exit program and move tool away to rotate insert and restart program from the beginning and cut air until we get back into the cut. We try to run from line but even if we call constant surface feed in our MDI spindle start the spindle runs at the cap RPM. If it is a consistent amount and predictable wear, one QD solution is to program to rough to half the amount, stop spindle, move tool, M1 to pause, change insert, S to restart, move tool back and restart cut. On a similar note, I have a lathe with a 6T Fanuc control. It will let you pause, move tool, do whatever, and restart cut, The caveat is that the tool has to be moved back to the EXACT position that you moved it from at pause. Ed. -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
On 21 November 2014 14:40, Jeff Johnson john...@superiorroll.com wrote: This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. I can think if a workaround, though it isn't especially nice, and a working jog-while-paused would be better. A PyVCP / GladeVCP or physical button could be added that feeds in an offset to the commmanded X and Z positions. In HAL this would be AND-ed with halui.program.is-paused so that the button is only active when the machine is paused, then it would operate a mux2 compionent that passes either 0 or the chosen retract through a Limit3 component and then to two offset components interposed between axis.0.motor-position-cmd and pid.0.command and between axis.2.motor-position-cmd and pid.2.command. So, when the machine is paused it is possible to press a HAL button that offsets the tool away from the work. This would only work for typical right-to-left cutting, where a positive offset in X and Y is what is needed. Of course adoption of one of the jog-while-paused options that have been coded would be a better solution. -- atp If you can't fix it, you don't own it. http://www.ifixit.com/Manifesto -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
You could place some tool change spots using block delete around where tool changes commonly occur. When the tooling starts to sound bad just toggle block delete on and change your tooling. Restart program and toggle BD off. -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
Honestly while I am sure there are ways to workaround that particular problem I have had many situations where a jog while paused feature would have come in very very handy. It is really something sorely missing from LinuxCNC. Hell even being able to just stop the spindle or turn off the coolant would be nice to check progress let alone being able to move tool away and inspect the work during a program. This is something that would be very useful in a multitude of operational situations. Peace Pete On Fri, Nov 21, 2014 at 10:03 AM, andy pugh bodge...@gmail.com wrote: On 21 November 2014 14:40, Jeff Johnson john...@superiorroll.com wrote: This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. I can think if a workaround, though it isn't especially nice, and a working jog-while-paused would be better. A PyVCP / GladeVCP or physical button could be added that feeds in an offset to the commmanded X and Z positions. In HAL this would be AND-ed with halui.program.is-paused so that the button is only active when the machine is paused, then it would operate a mux2 compionent that passes either 0 or the chosen retract through a Limit3 component and then to two offset components interposed between axis.0.motor-position-cmd and pid.0.command and between axis.2.motor-position-cmd and pid.2.command. So, when the machine is paused it is possible to press a HAL button that offsets the tool away from the work. This would only work for typical right-to-left cutting, where a positive offset in X and Y is what is needed. Of course adoption of one of the jog-while-paused options that have been coded would be a better solution. -- atp If you can't fix it, you don't own it. http://www.ifixit.com/Manifesto -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Pete Matos A and N Precision and Fabrication Maryville, Tennessee 865-236-8996 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
Block delete can't be changed while the program is running :( Honestly I don't think he was asking for a workaround. He is asking for utility. Unfortunately the developers that could do this don't see the need nor are intrigued by the technical issues to overcome. Or are working on a fork :) If the developers are not interested it's not going to get done. I wouldn't hold my breath for jog while paused. Chris M - Reply message - From: Lee Lancaster angrychi...@gmail.com To: Enhanced Machine Controller (EMC) emc-users@lists.sourceforge.net Subject: [Emc-users] Question for larger machine users of LCNC Date: Fri, Nov 21, 2014 7:07 AM You could place some tool change spots using block delete around where tool changes commonly occur. When the tooling starts to sound bad just toggle block delete on and change your tooling. Restart program and toggle BD off. -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
If this is in an ocode loop just write in a start offset n teeth so you dont need to cut air on the restart just rotate till offset and continue. Dave Caroline On 21/11/2014, Chris Morley chrisinnana...@hotmail.com wrote: Block delete can't be changed while the program is running :( Honestly I don't think he was asking for a workaround. He is asking for utility. Unfortunately the developers that could do this don't see the need nor are intrigued by the technical issues to overcome. Or are working on a fork :) If the developers are not interested it's not going to get done. I wouldn't hold my breath for jog while paused. Chris M - Reply message - From: Lee Lancaster angrychi...@gmail.com To: Enhanced Machine Controller (EMC) emc-users@lists.sourceforge.net Subject: [Emc-users] Question for larger machine users of LCNC Date: Fri, Nov 21, 2014 7:07 AM You could place some tool change spots using block delete around where tool changes commonly occur. When the tooling starts to sound bad just toggle block delete on and change your tooling. Restart program and toggle BD off. -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
On 21 November 2014 15:18, Chris Morley chrisinnana...@hotmail.com wrote: Unfortunately the developers that could do this don't see the need nor are intrigued by the technical issues to overcome. Or are working on a fork :) Well, there is that: https://github.com/machinekit/machinekit/pull/109 -- atp If you can't fix it, you don't own it. http://www.ifixit.com/Manifesto -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
[Emc-users] Question for larger machine users of LCNC
Message: 5 Date: Fri, 21 Nov 2014 09:40:04 -0500 From: Jeff Johnson john...@superiorroll.com Subject: [Emc-users] Question for larger machine users of LCNC To: emc-users@lists.sourceforge.net Message-ID: 00b201d00599$0a440730$ 1ecc1590$@superiorroll.com Content-Type: text/plain; charset=us-ascii This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. My question is how are others working around this? For instance I am working on a job machining gears with hardened teeth and we have to remove .250 form one face, roughing insert lasts about 2/3 of the way through the roughing program and we have to rotate the insert. Feed hold leaves us in a position too close to the part to change the insert. Our only solution is to exit program and move tool away to rotate insert and restart program from the beginning and cut air until we get back into the cut. We try to run from line but even if we call constant surface feed in our MDI spindle start the spindle runs at the cap RPM. I too, am unable to run from line with my lathe and have CSS work correctly. Dave -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
From: Ed ate...@mwt.net mailto:ate...@mwt.net Subject: Re: [Emc-users] Question for larger machine users of LCNC To: emc-users@lists.sourceforge.net mailto:emc-users@lists.sourceforge.net Message-ID: 546f5312.6050...@mwt.net mailto:546f5312.6050...@mwt.net Content-Type: text/plain; charset=ISO-8859-1; format=flowed On 11/21/2014 08:40 AM, Jeff Johnson wrote: This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. My question is how are others working around this? For instance I am working on a job machining gears with hardened teeth and we have to remove .250 form one face, roughing insert lasts about 2/3 of the way through the roughing program and we have to rotate the insert. Feed hold leaves us in a position too close to the part to change the insert. Our only solution is to exit program and move tool away to rotate insert and restart program from the beginning and cut air until we get back into the cut. We try to run from line but even if we call constant surface feed in our MDI spindle start the spindle runs at the cap RPM. If it is a consistent amount and predictable wear, one QD solution is to program to rough to half the amount, stop spindle, move tool, M1 to pause, change insert, S to restart, move tool back and restart cut. On a similar note, I have a lathe with a 6T Fanuc control. It will let you pause, move tool, do whatever, and restart cut, The caveat is that the tool has to be moved back to the EXACT position that you moved it from at pause. Ed. Every control (Cincinnati, Heidenhain, Fagor) we have in the shop has this ability except LCNC I have 9 Turning centers and 6 CNC mills. I understand free comes at a cost LOL...I currently have three Turning centers running LCNC and a vertical machining center in process of getting LCNC and I just bought a couple of VTL's with Fanuc 6T controls that will be retrofitted with something. I am running big work and insert and or cutter failures are common. Constant and predictable just does not come to light in our job shop environment I am sure it would in a production situation and I would gladly program around it. I am grateful to have found this software and glad we took the time tackle the learning curve as we are better off for it but as I said earlier there is a cost to pay and in our case this is one of them. Even if we could call up our spindle parameters in MDI and run from line (being very careful) it would be much better but as I pointed out in another post the G96 is for some reason ignored from MDI even though the flag does come up. Jeff Johnson john...@superiorroll.com Superior Roll Turning 734-279-1831 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
On 11/21/2014 06:40 AM, Jeff Johnson wrote: This is a question for people using LCNC on larger machine tools. We have been patiently waiting for jog while paused and it does not look like we are getting it anytime soon. My question is how are others working around this? For instance I am working on a job machining gears with hardened teeth and we have to remove .250 form one face, roughing insert lasts about 2/3 of the way through the roughing program and we have to rotate the insert. Feed hold leaves us in a position too close to the part to change the insert. Our only solution is to exit program and move tool away to rotate insert and restart program from the beginning and cut air until we get back into the cut. We try to run from line but even if we call constant surface feed in our MDI spindle start the spindle runs at the cap RPM. Jeff Johnson john...@superiorroll.com Superior Roll Turning 734-279-1831 Hi Jeff, It might be easier to fix the run from line than get the jog while paused. Arriving at the proper setting for start from line is a matter of scanning all the code up to the restart and setting the parameters correctly. I did this for tkemc years ago but naturally the code has disappeared and I'm not at all certain I could recreate it. Basically it has to do with setting all the codes before the restart that are modal. eg. build a small program that used gcode to set the parameters, stream all the remaining code to a temp file. Cat the parameter gcode to the front of the tmp file and run as a program. Not exactly elegant but it does work. Hope you didn't get too bored reading this. As for axis I have no idea what their internal approach is. Dave -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
I had heard that machinkit has the jog while paused or was going to be using it. Nice to see so much work going into it from a couple dedicated guys thank you. Was just talking to my friend Art and apparently even the turboCNC he uses has jog while paused. As I recall the HAAS machines we ran at work had the feature. It really is something very very useful in a lot of different situations. I know it was kinda buggy in Mach3 when I used it, well more than kinda but it was there and if you knew how to use it you could get it to work for you. On Fri, Nov 21, 2014 at 10:39 AM, andy pugh bodge...@gmail.com wrote: On 21 November 2014 15:18, Chris Morley chrisinnana...@hotmail.com wrote: Unfortunately the developers that could do this don't see the need nor are intrigued by the technical issues to overcome. Or are working on a fork :) Well, there is that: https://github.com/machinekit/machinekit/pull/109 -- atp If you can't fix it, you don't own it. http://www.ifixit.com/Manifesto -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Pete Matos A and N Precision and Fabrication Maryville, Tennessee 865-236-8996 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
On Fri, Nov 21, 2014 at 11:00 AM, Pete Matos petefro...@gmail.com wrote: I had heard that machinkit has the jog while paused or was going to be using it. Nice to see so much work going into it from a couple dedicated guys thank you. Was just talking to my friend Art and apparently even the turboCNC he uses has jog while paused. As I recall the HAAS machines we ran at work had the feature. It really is something very very useful in a lot of different situations. Just out of curiosity, I assume in most controls you have to manually ensure that the tool returns to the workpiece in a way that doesn't cause a crash. Or does it just record the jog path and reverse it? -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
As I recall we usually would jog away, take care of whatever needed addressing and then kinda jog near to where it was before but never precisely where it was before and hit go and it would take care of the rest. I honestly don't remember exactly how it worked just that it worked and we used it an awful lot in a job shop environment. here is a page I found on the HAAS setup and how it works... http://atyourservice.haascnc.com/expert-tip/run-stop-jog-continue/ On Fri, Nov 21, 2014 at 11:12 AM, Eric Keller eekel...@psu.edu wrote: On Fri, Nov 21, 2014 at 11:00 AM, Pete Matos petefro...@gmail.com wrote: I had heard that machinkit has the jog while paused or was going to be using it. Nice to see so much work going into it from a couple dedicated guys thank you. Was just talking to my friend Art and apparently even the turboCNC he uses has jog while paused. As I recall the HAAS machines we ran at work had the feature. It really is something very very useful in a lot of different situations. Just out of curiosity, I assume in most controls you have to manually ensure that the tool returns to the workpiece in a way that doesn't cause a crash. Or does it just record the jog path and reverse it? -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Pete Matos A and N Precision and Fabrication Maryville, Tennessee 865-236-8996 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
All the machines in our shop (Cincinnati Milacron, Fagor, Hermle, just to name a few) that are able to perform a jog move during a paused/feedhold state, take a straight and direct path back to where the pause was enabled, at whatever the maximum jog speed rate is. In saying this, we acknowledge that if we are say, cutting a bore in a part on a turning center, hit feedhold during a program, retract out, and jog up, replace or rotate the cutting insert, that you ABSOLUTELY HAVE TO jog back down to a point at or below where the cut was being made, or the obvious happens, you buy a new piece of material, and work on the machine for the next 2 shifts to replace broken taper pins, and realign the turret and whatever else broke in the mayhem. Thanks Rick -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
I am surprised to hear it RAPIDS back to the paused position. It would seem a slow move would be much safer or at a fraction of the commanded speed or something. On Fri, Nov 21, 2014 at 12:47 PM, Rick Lair r...@superiorroll.com wrote: All the machines in our shop (Cincinnati Milacron, Fagor, Hermle, just to name a few) that are able to perform a jog move during a paused/feedhold state, take a straight and direct path back to where the pause was enabled, at whatever the maximum jog speed rate is. In saying this, we acknowledge that if we are say, cutting a bore in a part on a turning center, hit feedhold during a program, retract out, and jog up, replace or rotate the cutting insert, that you ABSOLUTELY HAVE TO jog back down to a point at or below where the cut was being made, or the obvious happens, you buy a new piece of material, and work on the machine for the next 2 shifts to replace broken taper pins, and realign the turret and whatever else broke in the mayhem. Thanks Rick -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Pete Matos A and N Precision and Fabrication Maryville, Tennessee 865-236-8996 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
Not at a rapid rate, at the maximum jog rate, 50-60 ipm, not the 400-600 ipm for the rapids. Thanks Rick -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
If you read that HAAS control description of how their Run, stop, jog, continue works it seems to be pretty logical to me. It simply requires the OP to after he has jogged to wherever he need to jog back to a position CLOSE to where the pause happened initially and then hit a key and the machine then takes over jogging at 5% speed to the original position. This seems like a good idea and easier to get the machine to do. You will note that it does not allow for TLO changes which while important are not super critical in my view and apparently theirs too. The changing of an insert while typically not perfect should not change the offset that much and I guess it is understood that you would not want to do this on a critical dimension of a finish pass. It would sure be nice tho. Either way just having the ability to raise the millhead and turn the spindle and coolant on and off to take a quick measurement or inspect progress would be a big deal for me. Peace Pete On Fri, Nov 21, 2014 at 1:04 PM, Rick Lair r...@superiorroll.com wrote: Not at a rapid rate, at the maximum jog rate, 50-60 ipm, not the 400-600 ipm for the rapids. Thanks Rick -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users -- Pete Matos A and N Precision and Fabrication Maryville, Tennessee 865-236-8996 -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
I would have to agree with that from HAAS, it sounds like a pretty good description of what needs to happen. Thanks Rick Superior Roll Turning 399 East Center Street Petersburg MI, 49270 734-279-1831 www.superiorroll.com -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
Re: [Emc-users] Question for larger machine users of LCNC
On 11/21/2014 7:58 AM, Ed wrote: If it is a consistent amount and predictable wear, one QD solution is to program to rough to half the amount, stop spindle, move tool, M1 to pause, change insert, S to restart, move tool back and restart cut. On a similar note, I have a lathe with a 6T Fanuc control. It will let you pause, move tool, do whatever, and restart cut, The caveat is that the tool has to be moved back to the EXACT position that you moved it from at pause. Sounds like exactly what LCNC users want. (And everyone with a Torchmate plasma table!) Would it be possible to have a predefined pause and move command set that could be inserted into the code on the fly, pop it in immediately after the current line being executed? Hit the pause button, the code gets inserted to interrupt the machine. It stops the cut and moves to the location to service the tooling. Hit resume and it returns to the position to execute the next line of code, while the inserted commands get removed. It wouldn't work so well for when the current line has the machine moving a long distance before the next line will execute, but for code that has a lot of short movements it could do the job. --- This email has been checked for viruses by Avast antivirus software. http://www.avast.com -- Download BIRT iHub F-Type - The Free Enterprise-Grade BIRT Server from Actuate! Instantly Supercharge Your Business Reports and Dashboards with Interactivity, Sharing, Native Excel Exports, App Integration more Get technology previously reserved for billion-dollar corporations, FREE http://pubads.g.doubleclick.net/gampad/clk?id=157005751iu=/4140/ostg.clktrk ___ Emc-users mailing list Emc-users@lists.sourceforge.net https://lists.sourceforge.net/lists/listinfo/emc-users
